## Monday, April 08, 2013

### Creo Elements - More gears (yes more) spur gears, helical gears and herringbone gears

So I've done a couple of blog posts now on making gears, first by creating just a section of the gear. then replicating it around an axis
And by creating a big gear with a single tooth. then replicating it around an axis

Now I'll look at a third and final way of creating a spur gear, and show how this is also the way you need to make a helical gear, (with diagonal teeth) and a herringbone gear, (with herringbone -like little arrows teeth)

Even though this tutorial will show now to create all the gear types it's worth looking at the others, mostly because I'm only introducing the tools used once. so the lessons do build on top of each other, also, it's good to know more than one way of getting a part made.

We'll imagine the same scenario as the last post, that we have two axles 50mm apart and want two gears to link them.

The gears mesh together, so again we'll have the raise teeth of the gear protruding the 26mm radius, and the reciprocating grove in the gear at 24mm.

This time draw a circle that's 24mm.
pull the circle into a cylinder 20mm tall.
(you can pull to any height, but with the maths used later I'm using 20mm)

Now create a new work plane on that cylinder, draw guide lines for your tooth profile to be created, again at an angle of 5 degrees.

Once again draw a tooth profile onto the edge of the cylinder, your tooth crown should be 26mm from the centre.
Delete your guidelines that you've drawn and you're left with a single tooth on a cylinder again.

now clearly you can once again pull that tooth to 20mm height and replicate with rotational symetry, (like we did in the last two posts) to make another spur gear.

But this time I'm going to make a helical gear.

Select the axis as the centre of the cylinder part.

Now the pitch and turns are related.

Our part is 20mm high, therefore if we select 20 for the pitch and 1 for the turn, we'll get a single complete turn of the tooth profile all the way around the part.

But we want a tooth that progresses about 5 degrees around the part.

To progress 5 degrees around the part we need 5/360 turns (roughly 0.01)
and to keep the same pitch to turn ration (to make the tooth reach the top of the gear) we need the pitch to change to 20/0.01 = 2000

Now we need to mirror the part to create all the teeth.

since each tooth takes up 5 degrees we'll mirror 72 times, at an angle of 5 degrees.
Giving us a helical gear.

Now imagine that we want a steeper angle on those teeth.
go back to the part where there is just the outline of a single tooth ready to be added as a helix.

now imaging that we want the tooth to extend 20 degrees around the gear.
we need figure our the turns first.

360/20 =~0.04

then we need to figure out the pitch,
20 (gear height) / 0.04 (turns) = 500

Once again, use the rotational mirror tool to make 72 teeth with an angle of 5 degrees about an axis that is the centre of the gear.

HerringBone
Alternatively.
Before mirroring the tooth rotationally, to create a herringbone gear mirror the tooth along the face first.

now you'll have noticed that mirroring creates a lot of individual parts. We're going to apply the rotational symmetry to the herringbone gear that we are creating, so we want to group the parts into a single assembally so that we only need to perform the mirror opperation once.

fter creating the new assembaly (a1) drag the two parts (p1 and p1.1) into the assembly.

Now double click a1 you'll see the edge lines of the whole assembly are highlighted.

And apply the radial mirror tool to extend the gear teeth over the whole gear.